Tutorial - Modeling Lamp shade in SolidWorks method 1?

Sudhir Gill

8 Mar, 2012 08:41 AM

Here is the tutorial.

1. Step 1:

   Top plane >> Sketch.
   

   

2. Step 2:

   Draw a circumscribed polygon of 100mm diameter.
   

   

3. Step 3:

   Exit the sketch. Reference Geometry >> Plane.
   

   

4. Step 4:

   Offset the top plane by 80mm.
   

   

5. Step 5:

   Plane1>>Sketch.
   

   

6. Step 6:

   Draw a circle of 50mm dia.
   

   

7. Step 7:

   Select Lofted surface tool under surfaces tab and select both profiles.
   

   

8. Step 8:

   Planar surface tool under surfaces tab.
   

   

9. Step 9:

   Select the upper circular edges.
   

   

10. Step 10:

    Front plane >> Sketch.
    

    

11. Step 11:

    Draw a line.
    

    

12. Step 12:

    Exit the sketch and then Curves >> Project curve.
    

    

13. Step 13:

    Select the line and the face.
    

    

14. Step 14:

    Top surface >> Sketch.
    

    

15. Step 15:

    Draw this entity using rectangle and then fit spline tool.
    

    

16. Step 16:

    Exit the sketch and then Select Swept surface tool under surfaces tab.
    

    

17. Step 17:

    Select the spline as the profile and curve as the path.
    

    

18. Step 18:

    Reference Geometry >> Axis.
    

    

19. Step 19:

    Select Top plane and Origin.
    

    

20. Step 20:

    Circular pattern.
    

    

21. Step 21:

    Select the swept surface as the body to be patterned about axis 6 times.
    

    

22. Step 22:

    Trim surface tool under surfaces tab.
    

    

23. Step 23:

    Trim type be mutual and select all surfaces to trim. Under remove selection select all outer surfaces with swept surfaces.
    

    

24. Step 24:

    Click OK and the trim is performed.
    

    

25. Step 25:

    Thicken tool under surfaces tab and select the surface. Thicken it inside.
    

    

26. Step 26:

    Top face>>Sketch.
    

    

27. Step 27:

    Draw a circle of 20mm diameter.
    

    

28. Step 28:

    Extrude cut it by through all.
    

    

29. Step 29:

    Insert >> Feature >> Flex.
    

    

30. Step 30:

    Select the body as flex input and then twisting type flex. Adjust the tried to X=90.Y=Z=0. Now input the flex angle as 90º.
    

    

31. Step 31:

    Click OK and the part is generated.