Tutorial - Modeling 3 pipe joint in SolidWorks?

Sudhir Gill

12 Mar, 2012 03:47 AM

Here is the tutorial.

1. Step 1:

   Start SolidWorks.
   

   

2. Step 2:

   Top plane >> Sketch.
   

   

3. Step 3:

   Draw three equal construction line at 120º.
   

   

4. Step 4:

   Exit the sketch.
   

   

5. Step 5:

   Reference geometry >> Plane. Select the line and the end point. Click OK.
   

   

6. Step 6:

   Similarily create another plane for the line.
   

   

7. Step 7:

   Same step for third.
   

   

8. Step 8:

   Plane1 >> Sketch.
   

   

9. Step 9:

   Draw a circle of 50mm dia.
   

   

10. Step 10:

    Select Extruded surface under surface tab.
    

    

11. Step 11:

    Extrude it towards the Origin with a distance of 100mm.
    

    

12. Step 12:

    Plane2 >> Sketch.
    

    

13. Step 13:

    Draw circle of 50mm diameter.
    

    

14. Step 14:

    Extrude surface it with the same distance and towards the origin.
    

    

15. Step 15:

    Plane3 >> Sketch.
    

    

16. Step 16:

    Draw circle of 50mm diameter.
    

    

17. Step 17:

    Extrude surface it with the same distance and towards the origin.
    

    

18. Step 18:

    Top plane >> Sketch.
    

    

19. Step 19:

    Draw 3 lines collinear to each other and parallel to edge of pipe. These are 3 lines not one. This will create 3 edges.
    

    

20. Step 20:

    Exit the sketch and select trim surface under surfaces tab.
    

    

21. Step 21:

    Trim the surface using the line sketch as trimming tool.
    

    

22. Step 22:

    Similarily trim other two extrusions.
    

    

23. Step 23:

    Select lofted surface tool under surfaces tab.
    

    

24. Step 24:

    Select the edge of the pipe.
    

    

25. Step 25:

    And the corresponding edge of the other pipe.
    

    

26. Step 26:

    Under start/End constraints change them to Tangency to face. Click OK.
    

    

27. Step 27:

    Create the same feature for other two pipes.
    

    

28. Step 28:

    Same step for remaining two edges.
    

    

29. Step 29:

    Select Filled surface tool under surfaces tab.
    

    

30. Step 30:

    Select all upper the edges of the pipes.
    

    

31. Step 31:

    Change contact to tangent.
    

    

32. Step 32:

    Enable Apply to all edges. Click OK.
    

    

33. Step 33:

    Repeat the same step for lower side.
    

    

34. Step 34:

    Knit surface under surfaces tab.
    

    

35. Step 35:

    Select all surfaces and enable merge entities. Click OK.
    

    

36. Step 36:

    Now all surfaces are knitted into one.
    

    

37. Step 37:

    Select Thicken tool under surfaces tab.
    

    

38. Step 38:

    Select the surface knit and thickness be 2mm outside direction. Click OK.
    

    

39. Step 39:

    And the 3-pipe joint is created.