Tutorial - Making a pipe joint in SolidWorks?

Sudhir Gill

3 Feb, 2012 06:06 AM

Here is the Tutorial.

1. Step 1:

   Start Solidworks.
   

   

2. Step 2:

   Right plane>>Sketch.
   

   

3. Step 3:

   Draw a circle with diameter 60mm.
   

   

4. Step 4:

   Under Surface tab select extruded surface.
   

   

5. Step 5:

   Extrude surface it by 120mm with mid plane configuration.
   

   

6. Step 6:

   Click OK.
   

   

7. Step 7:

   Front Plane>>Sketch.
   

   

8. Step 8:

   Draw a circle with origin as center of 60mm diameter.
   

   

9. Step 9:

   Extrude surface it again with a height of 120mm diameter and mid plane configuration.
   

   

10. Step 10:

    Click OK.
    

    

11. Step 11:

    Top Plane>>Sketch.
    

    

12. Step 12:

    Draw this rectangular entity using lines. Remember I have not inserted any points but using lines. The points are differing line.
    

    

13. Step 13:

    Under Surfaces tab choose trim surface.
    

    

14. Step 14:

    Select the inner surfaces to trim.
    

    

15. Step 15:

    Click OK and you have some entity like this.
    

    

16. Step 16:

    Under Surfaces tab choose lofted surface.
    

    

17. Step 17:

    Select this edge of the surface.
    

    

18. Step 18:

    Again select the corresponding edge of the surface.
    

    

19. Step 19:

    Open Constraint settings and change start constraint to tangency to face.
    

    

20. Step 20:

    Change Close constraint to tangency to face.
    

    

21. Step 21:

    Click OK.
    

    

22. Step 22:

    Repeat the same step for other edges too.
    

    

23. Step 23:

    Under Surfaces tab choose Filled surface.
    

    

24. Step 24:

    Choose the edges enclosing open region.
    

    

25. Step 25:

    Change contact to Tangent.
    

    

26. Step 26:

    Check Apply to all edges.
    

    

27. Step 27:

    Choose OK.
    

    

28. Step 28:

    Repeat the same step for other surface too.
    

    

29. Step 29:

    Under surfaces choose Knit surface. This will knit down multiple surfaces into one.
    

    

30. Step 30:

    Select all Surfaces.
    

    

31. Step 31:

    Check Merge entities & click OK.
    

    

32. Step 32:

    Choose Thicken in Surfaces tab.
    

    

33. Step 33:

    Select the knit surface to thicken. Check thicken distance to 2mm.
    

    

34. Step 34:

    Change the thickness height to inside the region.
    

    

35. Step 35:

    Click OK and we have a pipe joint.